User subroutine interface
SUBROUTINE UEXPAN(EXPAN,DEXPANDT,TEMP,TIME,DTIME,PREDEF,
1 DPRED,STATEV,CMNAME,NSTATV,NOEL)
C
INCLUDE 'ABA_PARAM.INC'
C
CHARACTER*80 CMNAME
C
DIMENSION EXPAN(*),DEXPANDT(*),TEMP(2),TIME(2),PREDEF(*),
1 DPRED(*),STATEV(NSTATV)
user coding to define EXPAN, DEXPANDT and update
STATEV if necessary.
RETURN
END
Variables to be defined
- EXPAN(*)
-
Increments of thermal strain. The number of values to be defined and the
order in which they are arranged depend on the type of thermal expansion being
defined.
-
For isotropic expansion give the isotropic thermal strain increment as
the first and only component of the matrix.
-
For orthotropic expansion give ,
,
and
as the first, second, and third components of the matrix, respectively.
-
For anisotropic expansion give ,
,
,
,
,
and .
Direct components are stored first, followed by shear components in the order
presented here. For plane stress only three components of the matrix are
needed; give ,
,
and ,
as the first, second, and third components, respectively.
- DEXPANDT(*)
-
Variation of thermal strains with respect to temperature,
.
The number of values and the order in which they are arranged depend on the
type of thermal expansion being defined.
-
For isotropic expansion give the variation of the isotropic thermal
strain with respect to temperature as the first and only component of the
matrix.
-
For orthotropic expansion give ,
,
and
as the first, second, and third components of the matrix, respectively.
-
For anisotropic expansion give ,
,
,
,
,
and .
Direct components are stored first, followed by shear components in the order
presented here. For plane stress only three components of the matrix are
needed; give ,
,
and ,
as the first, second, and third components, respectively.
Variables that can be updated
- STATEV(NSTATV)
-
Array containing the user-defined solution-dependent state variables at this
point. Except for coupled temperature-displacement and coupled
thermal-electrical-structural analyses, these are supplied as values at the
start of the increment and can be updated to their values at the end of the
increment. For coupled temperature-displacement and coupled
thermal-electrical-structural analyses,
UEXPAN is called twice per material point per iteration. In the
first call for a given material point and iteration, the values supplied are
those at the start of the increment and can be updated. In the second call for
the same material point and iteration, the values supplied are those returned
from the first call, and they can be updated again to their values at the end
of the increment.
User subroutine
UEXPAN allows for the incremental thermal strains to be only
weakly dependent on the state variables. The Jacobian terms arising from the
derivatives of the thermal strains with respect to the state variables are not
taken into account.
Variables passed in for information
- TEMP(1)
-
Current temperature (at the end of the increment).
- TEMP(2)
-
Temperature increment.
- TIME(1)
-
Step time at the end of the increment.
- TIME(2)
-
Total time at the end of the increment.
- DTIME
-
Time increment.
- PREDEF(*)
-
Array containing the values of all the user-specified predefined field
variables at this point (initial values at the beginning of the analysis and
current values during the analysis).
- DPRED(*)
-
Array of increments of predefined field variables.
- CMNAME
-
User-specified material name or gasket behavior name, left justified.
- NSTATV
-
Number of solution-dependent state variables associated with this material
or gasket behavior type (specified when space is allocated for the array; see
Allocating space).
- NOEL
-
User-defined element number.
|